Check below the specifications and configurations available in the Weeke BHT 500 plugin:
Available from version: Plugin Builder 1.60.17.2
Machine Type: CNC Machining Center
Manufacturer: Weeke
Programs example: BAS0021A
Generated file extension: .mpr
Main features
- Holes;
- Slot;
- Machining;
- External contouring operations.
Settings
To check the settings on CNC Machines, click here.
Machine 1
General
Name: define the name for the machine.
IMPORTANT: The name set in this field also changes the name of the folder where the generated files will be saved.
Length (mm): length of the machine;
Width (mm): width of the machine.
Tools
To check the settings about CNC Tools, click here.
Mills
The mills are used to perform slotting and machining.
Contour Machining
Contour machining start: defines where contour machining starts, at one of the corners or in the middle of one of the workpiece edges. This option is applicable only to external contour machining.
External contour cut direction: defines whether contour machining has to be done clockwise or counterclockwise.
Internal Milling
Internal contour machining start: it defines internal machining to be made in a non-clockwise or anti-clockwise direction.
Internal milling cut direction: defines where internal contour machining starts, at one of the corners or in the middle of a machining edge.
Use cutting direction in single line operations: when you mark this setting, single-line machining operations follow the cutting direction of the mills. For more information, click here.
Lead in
Input type in linear machining: defines the type of input the tool will use when machining and contouring linear forms. Options Ramp, vertical, circular.
- Circular: in this type the tool descends outside the part and then starts cutting tangentially before entering the part.
- Vertical: in this type the tool descends vertically onto the workpiece and begins cutting.
- Ramp: in this type the tool descends by making a ramp until it reaches the maximum depth of operation.
Lead in extension (mm): extension of the entrance before the contour cutting starts, equivalent to the red line in the image.
Lead in/ Lead out
Distance between lead in and lead out (mm): distance the tool exits and enters the part. It is advisable that this value be greater than zero so that the cut does not leave any fragments (burrs).
Lead Out
Lead Out extension (mm): output extension after machining/contouring is finished, equivalent to the red line.
Lead Out Type: defines the type of output that the tool will use when machining and contouring.
- In the vertical type, the tool descends vertically onto the workpiece and begins cutting.
- In the circular type, the tool descends outside the part and then starts cutting tangentially before entering the part.
- In the ramp type, the tool descends as a ramp and starts cutting.
Properties
Code: the code defined in this field must match the registration defined on the machine so that the tool can be located correctly;
Diameter (mm): tool diameter;
Feed rate: tool's feed rate, the default value, is Standard;
Height (mm): tool height;
Name: the name defined in this field must match the registration defined on the machine so that the tool can be located correctly;
Overlap (mm): overpass between tool passes to avoid material leftovers;
Rotation speed: tool rotation speed, Standard is the default value used;
Step depth (mm): depth of tool step;
Through plunge and milling offset (mm): compensation of the drilling and machining of the part.
Saws
Saws are used to make slot.
Properties
Alignment: alignment of the saw, center, left or right;
Code: the code defined in this field must match the registration defined on the machine so that the tool can be located correctly;
Feed rate: tool's feed rate, the default value, is Standard;
In offset (mm): transfer between the passes of the hardware to avoid leftover material;
Name: the name defined in this field must match the registration defined on the machine so that the tool can be located correctly;
Orientation: tool orientation, vertical or horizontal;
Out offset (mm): saw output compensation for performing the cut, in millimeters. This setting is only applied if the slot ends outside or on the endpoint of the part;
Rotation direction: saw's rotation direction, Synchronous indicates default motion, and asynchronous indicates backwards motion;
Thickness (mm): thickness of the saw.
SetUps
General
Name: the name set in this field also changes the name of the folder where the generated files will be saved.
Alignment by face: defines whether the alignment face registered on each part is considered when generating programs. If yes, this face will be aligned according to the selected configuration. For more information, click here.
Perform drilling: machine is enabled to drill holes;
Perform machining: with the option checked, the registered machining operations will be generated in the machine programs;
Variable usage field distance, in X axis: distance relative to the end bound in X axis, which determines the area, where operations must consider the piece size variable minus the operation distance from end bound;
Variable usage field distance, in Y axis: distance relative to the end bound in Y axis, which determines the area, where operations must consider the piece size variable minus the operation distance from end bound;
Inverter variable fields: If this option marked, when a rotated piece is generated, the variable fields are inverted according to the image;
Machining processes: through Plugin Builder, it is possible to create and determine types of processes for machining registered in the library, thus enabling the use of a particular tool for a particular machining. For more information, click here;
Make slots: machine is enabled to make slots;
Perform machined contour: defines the contour of which parts will be generated.
- None: contour machining will not be generated for any part;
- All: contour machining will be generated for all parts;
- Only marked: contour machining will be generated only for parts that have the Machined Contour property enabled in the library register.
Slot processes: through the Plugin Builder, it is possible to create and determine types of processes for tears registered in the library, thus making it possible to use a certain tool for a certain tear. For more information click here.
Overcut
Sum edge band overcut: when overcutting with edge tape, it must be taken into account if the material is removed from the piece before applying the tape (gluer with entry router) since the cut size of the piece does not take into account the thickness of the edge tapes.
Sum plate overcut: panel overcut is typically used on parts that will need to be trimmed, such as wood hollow panel or composite top parts. Because due to the gluing of the pieces, they will be able to move, so with the overcut and the subsequent recut, the size used in the design is guaranteed.
Machine
Priorization order: defines the order of prioritization of operations for program generation. According to the order indicated in this field, the plugin will prioritize in program A, the selected option;
Example: In a part that has holes on one side and tears on the other side, the order indicated in this field will determine which of them will be prioritized in the A program;
Slot tool: tool used for slots. IMPORTANT: This option is available when the Make Slots option is selected.
Machining tool: tool used for machining. IMPORTANT: This option is only available when the option Machine Process is selected.
Contour tool: selected tools to perform contour operation;
Operations ordering: order that the machine performs operations.
Example: in a part that has holes and tears on the same face the order indicated in this field will determine the sequence in which they will be executed by the machine.
Holes
Drill bit angle used in through holes: determine the angle of the end of the drill bit for use with through holes. (from 25 to 90 degrees);
Drill GAP in through hole operation (mm): determine the clearance of the drill for use in through holes;
Maximum diameter of horizontal drill bit (mm): determine the clearance of the drill for use in through holes;
Maximum diameter of vertical drill bit (mm): maximum diameter of vertical drills;
Maximum drilling depth: maximum drilling depth, in millimeters;
Maximum position of horizontal drilling in (Y): maximum position where the machine can perform horizontal holes (X), in millimeters;
Maximum position of lateral drilling in (Y): maximum position where the machine can drill lateral holes in (Y), in millimeters;
Maximum position of vertical drilling in (Y): maximum position at which the machine can drill vertical holes in (Y), in millimeters;
Non-through drilling mode: drilling mode for non-through hole. There are two modes available, Slow-Fast and Fast-Fast;
Number of horizontal Drill bits (X): the number of drills, for each horizontal face, present in the machine;
Number of lateral Drill bits (Y): number of drill bits, for each side face, present in the machine;
Number of vertical Drill bits (Z): number of vertical drills present in the machine;
Through drilling mode: drilling mode for through holes. There are two modes available, Slow-Fast-Slow and Fast-Fast-Fast.
Machinings
Inverted pass: reverse pass used in edge-out operations.
- None: The cutter will follow the normal machining path entering one edge and exiting the other.
- One pass: The cutter will enter one edge of the part making only a small entry. Then the cutter will climb, go to the other end of the machining, and then follow the normal machining path.
- Double pass: The cutter will enter one edge of the part making only a small entry and return to the starting point. Then the cutter will climb, go to the other end of the machining, and then follow the normal machining path.
Slots
Maximum position for milled slots in (Y): maximum position where the machine can perform milled slots (Y), in millimeters;
Maximum position for sawed slots in (Y): maximum position where the machine can perform sawed slots (Y), in millimeters;
Minimum position for slots in (Y): minimum position where the machine can perform slots (Y), in millimeters;
Technical date:
Head displacement (FW): after the operations, check the option for the tool not to be above the part;
Maximum head displacement over X axis: maximum value for the head displacement in (X) after the operations;
Maximum thickness(Z): maximum thickness of the part that the machine can perform operations;
Minimum length (X): minimum thickness of the part that the machine can perform operations;
Minimum thickness (Z): minimum thickness of the part that the machine can perform operations;
Minimum width (Y): minimum part length for the machine to perform operations.
Example of Technical Drawing