Check below the specifications and configurations available in the DRILLTEQ V-200 plugin:
Available from version: Plugin Builder 1.60.20.3
Machine Type: CNC machining center
Manufacturer: Weeke | Homag
Programs example: COM0022A
Generated file extension: .mpr
Manual: manual available for the manufacturer, click here.
Main features
- Holes;
- Slot;
- Machining;
Settings
To check the settings on CNC Machines, click here.
Machine 1
General
Name: define the name for the machine.
IMPORTANT: The name set in this field also changes the name of the folder where the generated files will be saved.
Length (mm): length of the machine;
Width (mm): width of the machine.
Tools
To check the settings about CNC Tools, click here.
Mills
The mills are used to perform slotting and machining.
Contour Machining
Contour machining start: defines where contour machining starts, at one of the corners or in the middle of one of the workpiece edges. This option is applicable only to external contour machining.
External contour cut direction: defines whether contour machining has to be done clockwise or counterclockwise.
Internal Milling
Internal contour machining start: it defines internal machining to be made in a non-clockwise or anti-clockwise direction.
Internal milling cut direction: defines where internal contour machining starts, at one of the corners or in the middle of a machining edge.
Use cutting direction in single line operations: when you mark this setting, single-line machining operations follow the cutting direction of the mills. For more information, click here.
Lead in
Input type in linear machining: defines the type of input the tool will use when machining and contouring linear forms. Options Ramp, vertical, circular.
- Circular: in this type the tool descends outside the part and then starts cutting tangentially before entering the part.
- Vertical: in this type the tool descends vertically onto the workpiece and begins cutting.
- Ramp: in this type the tool descends by making a ramp until it reaches the maximum depth of operation.
Lead in extension (mm): extension of the entrance before the contour cutting starts, equivalent to the red line in the image.
Lead in/ Lead out
Distance between lead in and lead out (mm): distance the tool exits and enters the part. It is advisable that this value be greater than zero so that the cut does not leave any fragments (burrs).
Lead Out
Lead Out extension (mm): output extension after machining/contouring is finished, equivalent to the red line.
Lead Out Type: defines the type of output that the tool will use when machining and contouring.
- In the vertical type, the tool descends vertically onto the workpiece and begins cutting.
- In the circular type, the tool descends outside the part and then starts cutting tangentially before entering the part.
- In the ramp type, the tool descends as a ramp and starts cutting.
Properties
Code: the code defined in this field must match the registration defined on the machine so that the tool can be located correctly.
Diameter (mm): tool diameter;
Feed rate: tool's feed rate, the default value, is Standard.
Height (mm): tool height.
Name: the name defined in this field must match the registration defined on the machine so that the tool can be located correctly.
Overlap (mm): overpass between tool passes to avoid material leftovers.
Rotation speed: tool rotation speed, Standard is the default value used.
Step depth (mm): depth of tool step.
Tool Alignment
Define tool alignment type: defines the tool alignment type.
Tool compensation side in over the internal geometry: sets the tool compensation side in relation to the internal geometry. This setting does not affect the geometry points.
Saws
Saws are used to make slot.
Properties
Alignment: alignment of the saw, center, left or right.
Code: the code defined in this field must match the registration defined on the machine so that the tool can be located correctly.
Feed rate: tool's feed rate, the default value, is Standard.
In offset (mm): transfer between the passes of the hardware to avoid leftover material.
Name: the name defined in this field must match the registration defined on the machine so that the tool can be located correctly.
Out offset (mm): saw output compensation for performing the cut, in millimeters. This setting is only applied if the slot ends outside or on the endpoint of the part.
Rotation direction: saw's rotation direction, Synchronous indicates default motion, and asynchronous indicates backwards motion.
Thickness (mm): thickness of the saw.
Set Ups
General
Name: the name set in this field also changes the name of the folder where the generated files will be saved.
Alignment by face: defines whether the alignment face registered on each part is considered when generating programs. If yes, this face will be aligned according to the selected configuration. For more information, click here.
Perform drilling: machine is enabled to drill holes.
Make slots: with the option checked the registered slot will be generated in the machine programs.
Perform machining: with the option checked, the registered machining operations will be generated in the machine programs.
Variable usage field distance, in X axis: distance relative to the end bound in X axis, which determines the area, where operations must consider the piece size variable minus the operation distance from end bound.
Variable usage field distance, in Y axis: distance relative to the end bound in Y axis, which determines the area, where operations must consider the piece size variable minus the operation distance from end bound.
Inverter variable fields: if this option marked, when a rotated piece is generated, the variable fields are inverted according to the image.
Initial distance in Z for entry: possibility of specifying a numerical value for the following commands: AZ command: This command allows you to set the initial distance in Z for entry.
ZU command: This command allows you to set the input speed on the Z axis, especially useful for sensitive parts.
Machining processes: using the Plugin Builder, it is possible to create and determine types of machining processes registered in the library, thus making it possible to use a particular tool for a particular machining operation. For more information click here.
Remove command that sets speed in RPM: allows the "S_A = 'STANDARD'" command, which sets the rotation speed in RPM, to be removed. When the option is ON: The command is EXCLUDED from the machine program. When the option is UNCHECKED: The command remains in the machine program.
Slot processes: through the Plugin Builder, it is possible to create and determine types of processes for tears registered in the library, thus making it possible to use a certain tool for a certain tear. For more information click here.
Stop Command Processes: processes for stop commands.
Z-Axis input speed: speed for movement of sensitive parts.
Rotations
Evaluate minimum width for rotation: set when generating programs. The minimum dimension of the part to be rotated in the length direction will be evaluated. If selected, parts with a face smaller than the defined dimension will be rotated, with this face aligned with the machine's width axis.
Minimum length allowed for rotations (mm): defines the minimum length allowed for rotations, in millimeters. If the workpiece length is shorter than set, the largest dimension of the workpiece will be placed in X.
Machine
Priorization order: defines the order of prioritization of operations for program generation. According to the order indicated in this field the plugin will prioritize in program A the selected option.
Example: In a part that has holes on one side and tears on the other side, the order indicated in this field will determine which of them will be prioritized in the A program.
Slot tool: tool used for slots. IMPORTANT: This option is available when the Make Slots option is selected.
Machining tool: tool used for machining. IMPORTANT: This option is only available when the option Machine Process is selected.
Operations ordering: order that the machine performs operations.
Example: in a part that has holes and tears on the same face the order indicated in this field will determine the sequence in which they will be executed by the machine.
File .inf
Detail all programs operations: detail operations not performed in the .inf file in all programs (A, B. C .....).
Generate empty parts info: generate .inf file of parts without operations.
Holes
Drill bit angle used in through holes: determine the angle of the end of the drill bit for use with through holes. (from 25 to 90 degrees).
Drill GAP in through hole operation (mm): determine the clearance of the drill for use in through holes.
Maximum diameter of horizontal drill bit (mm): determine the clearance of the drill for use in through holes.
Maximum diameter of vertical drill bit (mm): maximum diameter of vertical drills.
Maximum drilling depth: maximum drilling depth, in millimeters.
Maximum position of the center of the horizontal holes opposite the Y axis of the lower face: maximum position of the center of the horizontal holes opposite the Y axis of the lower face.
Minimum position from the center of lateral hole in Y: minimum position from the center of the lateral holes in the Y axis that the lateral drills can operate, in millimeters.
Minimum position of the lower quadrant of the vertical holes (Qmin) on the Y axis: the lower quadrant of the hole must be at position Qmin from the bottom edge of the part. Where DY is the height of the workpiece. To calculate the position of the quadrant, consider the center of the hole in (Y) - (the radius of the hole).
Non-through drilling mode: drilling mode for non-through hole. There are two modes available, Slow-Fast and Fast-Fast.
Number of horizontal Drill bits (X): the number of drills, for each horizontal face, present in the machine.
Number of lateral Drill bits (Y): number of drill bits, for each side face, present in the machine.
Number of vertical Drill bits (Z): number of vertical drills present in the machine.
Through drilling mode: drilling mode for through holes. There are two modes available, Slow-Fast-Slow and Fast-Fast-Fast.
Machining \ Slots
Milled operation max length: operations carried out with milling cutters that are longer than the established length will be carried out in more stages.
Machining
Inverted pass: inverted pass used in side-edge exit operations.
- None: the milling cutter will follow the normal machining path entering one edge and exiting the other.
- One pass: the milling cutter will enter one edge of the part, making only a small entry. Then the cutter will climb, go to the other end of the machining, and then follow the normal machining path.
- Double pass: the milling cutter will enter one edge of the part making only a small entry and return to the starting point. Then the cutter will climb, go to the other end of the machining, and then follow the normal machining path.
Machining direction: defines the behavior of the machining direction: default follows the operation registration; forcing clockwise performs the machining.
Machining type: defines the behavior of through machining. Default: follows the operation registration. Force Empty: removes all material. Force Contour: performs only the contour of the operation. For more information click here.
Minimum working position Y for mill at the superior face (mm): minimum Y position at which the mill can work, at the face of the cutter.
Slots
Minimum position of the lower quadrant of the vertical slots on the Y axis: minimum position of the lower quadrant of the vertical slots on the Y axis.
Technical Data
Maximum thickness(Z): maximum thickness of the part that the machine can perform operations.
Minimum length (X): minimum thickness of the part that the machine can perform operations.
Minimum thickness (Z): minimum thickness of the part that the machine can perform operations.
Minimum width (Y): minimum part length for the machine to perform operations.
Example Technical Drawing